PCB Copper Thickness: 1 oz, 2 oz and Heavy Copper Guide
Short answer: PCB copper thickness is usually specified as copper weight in ounces per square foot. 1 oz copper is about 1.37 mil (roughly 35 µm) thick, 0.5 oz is about half that, and 2 oz is about 2.74 mil (roughly 70 µm). Most boards use 1 oz finished copper on outer layers and 0.5 …
Short answer: PCB copper thickness is usually specified as copper weight in ounces per square foot. 1 oz copper is about 1.37 mil (roughly 35 µm) thick, 0.5 oz is about half that, and 2 oz is about 2.74 mil (roughly 70 µm). Most boards use 1 oz finished copper on outer layers and 0.5 or 1 oz on inner layers. Move to 2 oz or heavy copper only when current, heat or voltage drop demand it, because thicker copper raises the minimum trace width and spacing, changes impedance, and adds cost.
Cross-section of a multilayer PCB with copper layers of different thicknesses, fiberglass cores and plated through vias
What does copper weight in ounces mean?
PCB fabricators describe copper by weight, not by thickness. “1 oz copper” means that one ounce of copper is spread evenly over one square foot of board. At copper’s density, that gives a layer about 1.37 mil thick, which is close to 35 µm. Double the weight and you roughly double the thickness.
This unit comes from how copper foil is sold, and it is still the language most fabs, quotes and stackup drawings use. When you read “1 oz” on a fab drawing, read it as “about 35 µm of copper”, then check whether the drawing means base foil or finished thickness (more on that below).
PCB copper thickness chart
Approximate nominal values, using 1 oz ≈ 1.37 mil ≈ 34.8 µm:
Copper weight
Thickness (mil)
Thickness (µm)
Typical use
0.5 oz
~0.69
~17
Inner signal layers, fine-pitch outer layers before plating
1 oz
~1.37
~35
Default for most outer and many inner layers
2 oz
~2.74
~70
Power planes, higher-current traces, better heat spreading
3 oz
~4.1
~105
Power supplies, motor drives, heavy copper boards
4 oz
~5.5
~140
High-current busbars on the board, heavy copper
These are nominal values. Real finished copper varies with foil tolerance, plating, and how much copper is removed by cleaning and etching. Your fab’s stackup and the finished-copper tables in IPC-6012 tell you what to expect after processing.
Base copper vs finished copper
This is the most common source of confusion with copper thickness.
Inner layers are mostly not plated. What you specify as foil (for example 1 oz) is close to what you get, minus some loss during processing.
Outer layers usually start with thinner base foil, often 0.5 oz, and are then plated up when the holes are plated. The finished outer copper ends up thicker than the starting foil.
So “1 oz outer” can mean 1 oz base foil (finishing thicker after plating) or 1 oz finished copper (starting from thinner foil). Write on your fab drawing which one you mean, ideally as a finished thickness in µm or mil, and confirm it against the fab’s stackup.
How copper thickness affects your design
Current capacity and temperature rise
A trace’s current capacity depends on its cross-section and how well it sheds heat. Thicker copper gives more cross-section at the same width, so a 2 oz trace can carry a given current at a narrower width than a 1 oz trace for the same temperature rise. Size traces with IPC-2152 charts or a calculator based on them, rather than old rules of thumb. Our PCB trace width and current capacity guide walks through the method.
Voltage drop and plane resistance
Copper resistance falls as thickness rises. On long power paths and low-voltage, high-current rails, voltage drop can matter more than temperature rise. Thicker planes, or more plane layers, reduce that drop. A solid PCB ground plane on 1 oz copper is often enough for signal returns, while power stages may need 2 oz or more.
Heat spreading
Thick copper spreads heat away from hot parts such as regulators, MOSFETs and LED arrays. It works best together with thermal vias that carry heat into inner planes. The flip side: thick planes also pull heat away from pads during soldering, so thermal reliefs and reflow profiles need more attention.
Impedance
Copper thickness is one of the inputs to trace impedance. Thicker copper slightly lowers the impedance of a trace at the same width, and it changes the trapezoidal shape left by etching. Always enter the finished copper thickness in your field solver and agree it with the fab. See our controlled impedance PCB design guide for the full workflow.
Minimum trace width and spacing
Etching removes copper sideways as well as downward. The thicker the copper, the more undercut you get, so fabs set larger minimum trace widths and gaps for thicker copper. Fine-pitch BGAs and QFNs can be hard to fan out on thick outer copper. Check your fab’s capability table for each copper weight before you commit, and treat it as part of your PCB DFM review.
Stackup, lamination and warpage
Thick inner copper leaves deep gaps between features that resin has to fill during lamination. That can need more or different prepreg, which changes dielectric thickness and impedance. Unbalanced copper (for example heavy copper on one side and light on the other) raises the risk of bow and twist. Keep copper weights and copper density roughly symmetric around the center of the PCB stackup.
Cost and lead time
More copper means more material, longer plating and etching, and tighter process control. 2 oz is widely available, while heavy copper builds narrow the list of suitable fabs and usually cost more and take longer.
When to use heavy copper PCB
Heavy copper is often defined as 3 oz per square foot or more, though fabs draw the line differently. It makes sense for:
Power supplies, chargers and inverters with high continuous currents
Motor drives and battery management systems
Boards that must survive overload or fault currents
Designs that would otherwise need external busbars or wire jumpers
Before choosing heavy copper, compare it with alternatives: wider traces, parallel layers tied together with via arrays, more plane layers on standard copper, or a dedicated busbar. These options can be cheaper and keep fine-pitch routing possible on the signal layers.
How to choose copper thickness: a practical workflow
List the high-current nets and their continuous and peak currents, plus the allowed temperature rise and voltage drop.
Start with 1 oz finished outer and 0.5 or 1 oz inner as the baseline for signal layers.
Size the power paths with IPC-2152 data. If the needed widths do not fit, try parallel layers first, then 2 oz.
Check fine-pitch parts against your fab’s minimum trace and space for the chosen outer copper.
Recalculate impedance with the real finished thickness and the fab’s stackup.
Balance the stackup so copper weights mirror around the center.
State finished thickness on the fab drawing and confirm it with the fabricator before release.
Common copper thickness mistakes
Mixing up base and finished copper on outer layers
Using a 1 oz trace width calculation for a board built on 0.5 oz inner copper
Choosing 2 oz outer copper and then routing a 0.4 mm pitch BGA on it
Leaving impedance calculations at a default thickness that differs from the fab’s stackup
Putting heavy copper on one side only and getting a warped board
Forgetting that thick planes need thermal reliefs on hand-soldered or through-hole pads
These issues are easy to miss in a manual PCB design review because they live in different places: the stackup, the fab notes, the net classes and the footprints.
Where AI and automated checks help
Copper thickness decisions touch many rules at once. AI-assisted design checks can compare current requirements against trace widths for the actual copper weight on each layer, flag fine-pitch footprints that break the fab’s minimum trace and space for thick copper, catch impedance rules that assume a different thickness than the stackup, and point out unbalanced copper before the board goes to quote. IntelCAD brings these checks together with component selection, so the parts you choose and the copper you route them on are reviewed as one design.
FAQ
How thick is 1 oz copper on a PCB?
1 oz copper is about 1.37 mil, or roughly 35 µm, thick. It is the most common copper weight for PCB outer layers.
What is the difference between 1 oz and 2 oz copper?
2 oz copper is about twice as thick as 1 oz, roughly 70 µm instead of 35 µm. It carries more current at the same trace width and spreads heat better, but it needs wider minimum traces and gaps and usually costs more.
What is heavy copper PCB?
A heavy copper PCB uses thick copper layers, often defined as 3 oz per square foot or more, for high-current or high-heat designs such as power supplies and motor drives. The exact threshold varies by fabricator.
Does copper thickness affect impedance?
Yes. Thicker copper slightly lowers a trace’s impedance at the same width, so impedance calculations should use the finished copper thickness from the fab’s stackup.
Is outer layer copper thicker than inner layer copper?
Often yes. Outer layers are usually plated during hole plating, so finished outer copper ends up thicker than the starting foil, while inner layers stay close to their foil thickness.
Next step
Want every power trace checked against the real copper weight on its layer before you order boards? Start Your Design with IntelCAD for AI-assisted PCB design, component selection and manufacturability checks.